Maximum and least material condition (MMC, LMC): definition and bonus tolerance
Which size is which
| Feature | MMC size | LMC size |
|---|---|---|
| Hole (internal) | Smallest allowed diameter | Largest allowed diameter |
| Pin or boss (external) | Largest allowed diameter | Smallest allowed diameter |
A worked example
A hole is Ø8.00 to Ø8.20 with position 0.20 at MMC. MMC size is 8.00. The measured hole is 8.10, so the bonus is 8.10 - 8.00 = 0.10 and the allowed position is 0.30. A position error of 0.28 passes, although it is over 0.20. Try it in the calculator. The numbers are an example, not from a real drawing.
Common mistakes
- Granting bonus in the wrong direction for a pin.
- Applying bonus when the frame has no M.
Reading the letters
The modifier is a circled letter after the tolerance (or after a datum letter) in the feature control frame. M means maximum material condition, L means least material condition, and no letter means the tolerance applies regardless of feature size, which is the default reading. The distinction matters because a modifier turns a fixed tolerance into one that depends on the measured size.
A worked outside-diameter example
A pin is made to a diameter of 7.80 to 8.00 with a perpendicularity tolerance of 0.05 at MMC. MMC for a pin is its largest size, 8.00. The measured pin is 7.90, which is 0.10 below MMC, so the bonus is 0.10 and the allowed perpendicularity is 0.15. A perpendicularity error of 0.12 passes. If the pin were exactly 8.00, only 0.05 would be allowed. These numbers are an example, not from a real drawing.
Why designers use it
MMC is used where parts must assemble. A small hole in a bracket and a large pin in a mating part are the worst case for fit, so the design allows more position error when the hole is larger. It lets a manufacturer accept parts that would assemble anyway. LMC is used for other purposes, such as keeping a minimum wall thickness.
Reporting
Record the measured size, the position or form result and the allowed value including the bonus, so that a reviewer can see how the verdict was reached. The true position calculator does the bonus arithmetic for holes and pins.
Worked example on the sample's hole callout
The sample's four holes are diameter 9.0 plus or minus 0.1 through, so their smallest allowed size, the MMC size, is 8.9 and their largest is 9.1. The sample has no position frame, so imagine one reading 0.30 with a circled M. The demonstration result of balloon 6 is 9.05, which is 0.15 above 8.9, so the bonus is 0.15 and the allowed position error is 0.45. A hole at 9.10, the largest allowed, would get a bonus of 0.20 and an allowance of 0.50. A hole at 8.90 gets no bonus and only 0.30.
| Hole size | Bonus | Allowed position error |
|---|---|---|
| 8.90 (MMC) | 0.00 | 0.30 |
| 9.05 (sample result) | 0.15 | 0.45 |
| 9.10 (LMC) | 0.20 | 0.50 |
RFS, MMC and LMC side by side
Regardless of feature size, written without a modifier, means the tolerance is fixed. MMC lets it grow as the feature moves toward its least-material size. LMC lets it grow as the feature moves toward its maximum-material size. The three change only how much tolerance you have, never where the true position is.
Mistakes inspectors make
- Applying bonus when the frame has no modifier.
- Using the wrong end of the size range as MMC for a pin and a hole.
- Forgetting that a bonus applies to the tolerance, not to the size limits.
- Measuring size loosely, which makes the bonus meaningless.
- What is maximum material condition?
- The size at which a feature holds the most material: smallest hole, largest pin.
- What is least material condition?
- Least material condition, LMC, is the size at which a feature has the least material: the largest hole or the smallest pin. A frame with an L lets the tolerance grow as the feature departs from that size.
- What does the M in a circle mean?
- It marks maximum material condition. Where it follows a tolerance in a frame, the tolerance can grow by the amount the feature's size differs from its MMC size, which is called bonus tolerance.